Creating a Shellable Feature

You can create a shellable prism using the Shellable Feature command. It is very often used to create the part's main shape.

This task shows you how to create a shellable prism.

Before you begin: Sketch a rectangle in the Sketcher workbench then return to the Functional Modeling Part workbench.
Related Topics
Creating a Shellable Feature
Creating Basic Features
About Basic Features
Setting Shell Properties
Using the Display Only Parents Option to Retrieve a Creation Context

  1. Click Shellable Feature in the Basic Features toolbar.

    Shellable features can have different basic shapes: Prism, Sweep, Revolve, Thick Surface or an External Shape. The Shellable Feature dialog box that appears displays Prism as the default shape to be created.



  2. If you prefer a different shape, click any of the other four shapes available.

  3. Select the profile you want to extrude.



    Tip: If no profile is defined, clicking Sketcher enables you to sketch the profile you need.

  4. Create a basic prism as explained in the Prism task.

  5. Click OK to confirm and create the shellable feature.

    Shellable Prism.X is added to the specification tree in the Solid Functional Set.X node.

    By customizing the view (using Hidden edges points), you can notice that the prism is hollow . By default, the shellable feature has no opening.



  6. To open it, just double-click the Shellable Prism.1 node in the specification tree or click Shell Properties in the Mold Design Properties toolbar.

  7. For example, select the top face as the face to be removed and enter the value of your choice to define the wall thickness.

  8. Click OK to confirm the operation.

    One face has been removed.