Create a front view
You can create the front view either from a part or from the sub-part of
a product, using a reference plane.
Click Front View
in the Views toolbar.
To define the reference plane, select either of the following:
- A plane of the 3D part or a plane surface.
- Two edges: these edges correspond to both axes defining
the reference plane according to which the front view will be generated.
The first edge determines the horizontal axis.
- A point and an edge, an edge and a point, two points and
an edge, or three points: you will thus define a plane.
Blue arrows appear, enabling you to redefine the projection
plane before generating the view. For more information, refer to
Define the
view orientation during view creation.
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Click in the drawing to generate the view.
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Define the
view orientation during view creation
When creating a view, you can redefine the orientation of its reference
plane using the available arrows.
This is the case when
generating a front view, an
isometric view or when generating
views using the wizard.
Open a 3D part representation and start creating a front view.
Click the right or left arrow to visualize the right or left
side, respectively.
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Click the bottom arrow to visualize the bottom side.
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Click the counterclockwise arrow to rotate the reference
plane.
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Drag the green knob to redefine the rotating angle. The default
increment value is 30 degrees.
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You can modify the increment value using the
contextual menu, which is available for the
green knob. To do this, right-click the knob and select
the desired option: - Free hand rotation: Lets you rotate the knob
in a free manner using the mouse, instead of snapping it to a given increment.
- Incremental hand rotation: Snaps the rotation
to a given increment (from 30 to 30 degrees, between zero and 330). This
is the default value.
- Set increment...: Displays the Increment
Setting dialog box. Enter the required value in the Increment
value field. For example, type 5 deg (for 5 degrees) and click
OK.
- Set current angle to:
-
0 deg: Sets the current angle value to 0 degrees.
-
90 deg: Sets the current angle value to 90
degrees.
-
180 deg: Sets the current angle value to 180
degrees.
-
270 deg: Sets the current angle value to 270
degrees.
-
Set angle value...: Displays the Angle
Setting dialog box. Enter the required value in the current
angle (deg) field. For example, type 30 and click
OK.
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Create a front view with a local axis system
This functionality allows you to take into account a local axis system when
creating a view. That way, the origin of the generated view is the projection
of the origin of the local axis system selected in the view plane.
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Click Front View
in the Views toolbar.
In the part specification tree, select the local axis system,
Axis System.1.
Select one plane of the 3D part or a plane surface, to define
the reference plane.
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Click in the drawing to end the view creation. The part local
axis system appears in the view.
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Create a front view from specific sub-bodies/sub-products
You can multi-select specific sub-products in a product and/or several sub-bodies
in a part to create front views displaying the selected elements only. These
multi-selected 3D elements will be previewed and then used as reference planes
for generating several front views.
Open a 3D product.
Click Front View
in the Views toolbar.
Select one body, or press the Ctrl key and then
multi-select the desired elements in the specification tree.
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In the 3D, point to the geometry to choose a projection plane.
As you go over the geometry with the cursor, the oriented preview automatically
appears on the 3D document.
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When the oriented preview corresponds to the projection plane
you want, click the plane to validate.
The front view is previewed. At this point, you can still
modify its orientation:
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Click in the drawing to generate the view.
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Create a front view using selection sets
Selection sets let you gain in productivity, particularly in the case of
large assemblies, when generating several views with numerous common features:
you can select and store these features once and reuse the selection set as
often as necessary without having to select the features again.
Open a 3D product.
Before you start creating views from selection sets, you
first need to create one or more selection sets for this product. For more
information, refer to Infrastructure User's Guide: Storing Selections Using Selection. For example, create a selection
set to store product screws.
Click Front View
in the Views toolbar.
Activate the product representation and select Edit > Selection
Sets...
In the Selection Sets Selection dialog box that
is displayed, select a selection set and click the Select button.
The selection
set items are highlighted in the 3D and in the specification tree. For more information, refer to Infrastructure User's Guide: Selecting Selection
Sets.
In the 3D, point to the geometry to choose a projection plane.
As you go over the geometry with the cursor, the oriented preview automatically
appears on the 3D document.
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When the oriented preview corresponds to the projection plane
you want, click the plane to validate.
The front view is previewed. At this point, you can still
modify its orientation:
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Click in the drawing to generate the view.
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