Removing a Shape

You can modify one or more features by removing a shape from it using the Remove Feature command. The removing shape can be a prism, a sweep, a revolve, a thick surface or the shape of an external body or surface.

This task shows you how to remove a sweep from a shellable prism.

Related Topics
Using the Display Only Parents Option to Retrieve a Creation Context

  1. Click Remove Feature in the Dress up & Modifiers toolbar (Feature Modifiers sub-toolbar).

    The Remove Feature dialog box appears.



  2. Select Pocket.1 as the feature to modify.

    If you select several features, the box displays the number of selected elements. To act on this selection, just click to display the Features to modify list dialog box that allows you to:

    • View the selected elements
    • Remove any element by clicking the Remove button
    • Replace any element using the Replace button and selecting a new one in the geometry or the specification tree.

  3. Click Sweep in the Remove Feature dialog box.

    Remove features can have different shapes. The prism is the default shape. If you prefer a different shape, click any of the other three shapes available. To know how to create any of them, refer to the Prism, Sweep, Revolve, Thick Surface or External Shape tasks.

  4. Select Profile_sketch as the Profile/Surface defining the sweep and Center_Curve as the center curve.

  5. In the Fillet tab, select the Lateral radius check box.

  6. Enter 1mm as the lateral radius value.

    Important: You can select the Draft fillets check box from the Fillet tab. For more information, see More About Draft Fillets.

  7. Click Preview.

    The defined sweep has been removed from the shellable prism. Remove Sweep.X is added to the specification tree in the Solid Functional Set.X node.



  8. Select Intersection radius checkbox and enter 1mm.

    Intersection radius provides the capability to create fillets at the intersections with the targets. Also it provides the ability to keep the wall thickness constant when modifying wall creating feature that has set the constant wall option. In this case, the fillets are added at the intersections with the shellable prism.

  9. Click OK to confirm the operation.