Creating a Sequential Groove Operation

You can create a Sequential Groove operation.

Related Topics
Sequential Axial and Sequential Groove Operations

  1. Open a typical part with two grooves to machine like the one shown below:

  2. Activate the Manufacturing Program and click Sequential Groove in the Axial Machining Operations toolbar.

    A Sequential Groove entity is added to the Manufacturing Program.

    The Sequential Groove dialog box appears directly at the Geometry tab . This tab includes a sensitive icon to help you specify the geometry. Areas of the icon are colored red indicating that this geometry is required

  3. Still in the Geometry tab.

    See Selecting Geometry

    1. Go to the Global tab to define the hole geometry to machine.
    2. Select the red groove depth representation in the sensitive icon, then select the two holes in the part.
    3. Set the Number of levels to 2.
    4. Double click to end your selections.



    5. Go to the Local tab to define the machining planes to reach.
    6. For Level Number 1, select the plane representations in the sensitive icon, and the planes of the first groove in the part.

      The Local tab is updated as shown below.

    7. For Level number 2, select the appropriate planes of the second groove in the part.

  4. Select the Strategy tab , which comprises two tabs Motions (to define the elementary motions making up the machining operation) and Strategy.

    1. Go to the Motions tab.
    2. Click Go to Plane , then define a Go to Plane motion to Plane 1 and a Local Feedrate of 50mm/mn. Set Compensation to 2.



    3. Click OK to add the first tool motion in the list in the Sequential Groove dialog box.
    4. Click Circular , then define a circular motion



    5. If necessary, adjust the radius of the circular approach (and circular retract) portion of this motion to be compatible with the groove and tool radius values.
    6. Right-click the circular arc in the icon, and set the radius parameter to 5mm.
    7. Click OK to add the motion in the list
    8. Click Go to Plane , then define a Go to Plane motion to Plane 2 and a Local Feedrate of 50mm/mn. Set Compensation to 1.



    9. Click OK to add the tool motion in the list.
    10. Insert other motions as follows:


      • Circular motion with Feedrate=Machining

      • Go to Clearance motion with Local Feedrate of 500mm/mn. Right-click this motion in the list and set the Application mode to Last level.



    11. Go to the Strategy tab .
    12. Specify machining parameters such as Approach clearance.
    13. Make sure the Compensation application mode is set to Guiding Point.

  5. Go to the Tool tab to select a tool.

    See Specifying a Tool Element in a Machining Operation

    1. Select a T-slotter tool and set the nominal diameter to a value less that 40mm (so that the tool can pass through the top of the hole).
    2. Click More >> and go to the Compensation tab to specify a second corrector P2 as follows:



  6. Select the Feeds and Speeds tab to specify the feedrates and spindle speeds for the operation.

  7. Select the Macros tab to specify the desired transition paths.

    See Defining Macros on Axial Machining Operations

  8. Click Tool Path Replay to check the validity of the operation.

    See Replaying the Tool Path


    • The tool path is computed.
    • A progress indicator is displayed.
    • You can cancel the tool path computation at any moment before 100% completion.



  9. Click OK to create the operation.