PP Tables and PP Word Syntaxes

PP Word Tables

You can create and manage Post-Processor word tables within Machine Programming.

General Information

Sample PP word tables are delivered with the product in the folder ..\startup\manufacturing\PPTables

A PP word table:

is stored in a unique text file with suffix pptable.
can be used as a basis for creating user-defined tables.
can be defined for a specific machine tool and used in NC applications.
comprises:
- major words without parameters
- major words with a text
- major words with parameters
- minor words
- word syntaxes

You can define the general syntaxes of post-processor words:

syntaxes associated to particular NC commands.
See Define PP Word Syntax.
sequences of PP word syntaxes associated to particular NC instructions.
See Define PP Word Syntax.

These syntaxes are proposed when you want to create a PP instruction.

Default Values

Some NC commands and NC instructions have default values.

Important: The default value is output even when the NC command or NC instruction is not present in the PP table.

The example below shows an NC command with explicit definition:

	*START_NC_COMMAND     NC_CHANGE_REF_PT 
	SWITCH/%MFG_QUADRANT 
	*END

If this output is not required, you must define an empty NC command or NC instruction. For example:

	*START_NC_COMMAND     NC_CHANGE_REF_PT 
	*END

TPRINT and NOTE

PRINT and NOTE are automatically included in the lists of major words with parameters and minor words respectively, even if they are not specifically declared in the PP word table.

NC Commands

For a given machine tool (i.e. post-processor), you can define PP word syntaxes associated to particular NC commands.

A NC command is a machine function such as a feedrate declaration (NC_FEEDRATE) or a spindle activation (NC_SPINDLE_START).

A syntax comprises a major word and one or more syntax elements such as minor words, numerical values, lists and parameters.

A syntax that includes lists or parameters is a parameterized syntax.

Parameterized Syntax

This is an example of parameterized syntax

	*START_NC_COMMAND     NC_COMPENSATION 
	LOADTL/%MFG_TL_NUMBER,%MFG_TOOL_COMP 
	*END

Notes:

The & character indicates a list and the % character indicates a parameter.
A list has a finite number of values.
You can define only one syntax for each NC command.

The examples below show how lists can be used to define units for feeds and speeds.

Example: Defining Inch Units for Feeds and Speeds

	*START_NC_COMMAND         
	NC_FEEDRATE 
	*START_LIST MFG_FEED_UNIT  
	IPM ,IPR  
	*END  
	FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT 
	*END 
	/ 
	*START_NC_COMMAND         NC_SPINDLE_START 
	*START_LIST MFG_SPNDL_UNIT  
	RPM ,SFM  
	*END 
	SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY 
	*END 
	/ 
	*START_NC_COMMAND         NC_SPINDLE_LATHE 
	*START_LIST MFG_SPNDL_UNIT  
	RPM ,SFM  
	*END  
	SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT 
	*END

Example: Defining Metric Units for Feeds and Speeds

	*START_NC_COMMAND         
	NC_FEEDRATE 
	*START_LIST MFG_FEED_UNIT  
	MMPM ,MMPR  
	*END  
	FEDRAT/%MFG_FEED_VALUE,&MFG_FEED_UNIT 
	*END 
	/ 
	*START_NC_COMMAND         NC_SPINDLE_START 
	*START_LIST MFG_SPNDL_UNIT  
	RPM ,SMM  
	*END 
	SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT,&MFG_SPNDL_WAY 
	*END 
	/ 
	*START_NC_COMMAND         NC_SPINDLE_LATHE 
	*START_LIST MFG_SPNDL_UNIT  
	RPM ,SMM  
	*END  
	SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT 
	*END

For an example of how to define syntaxes in NC commands, refer to Define PP Word Syntax.

Arithmetic Operators

You can use the following arithmetic operators in PP word syntaxes:

addition (+)
subtraction (-)
multiplication (*)
division (/).

These operators can be used:

between word syntaxes (for example, %MFG_xxx + %MFG_yyy)
between a value and a word syntax (for example, n + %MFG_yyy)
between a word syntax and a value (for example, %MFG_xxx + n)
between values (for example, n + m).

Parenthesis are not needed in expressions: they can be ignored and cannot appear in NC data output. For example:

WORD/%MFG_aaa, %MFG_xxx + %MFG_yyy, %MFG_bbb/2

Operators are processed in the order they appear in the syntax: the example below means that %MFG_xxx is added to %MFG_yyy, then this sum is multiplied by %MFG_zzz.

%MFG_xxx + %MFG_yyy * %MFG_zzz

Note: Avoid using the +, -, *, / characters for other meanings. For example, use an underscore (_) instead of a dash (-) in the following expression to avoid any ambiguity:

PPRINT/DIAMETER-VALUE, %MFG_NOMINAL_DIAM

Start Comments

You can use NC_xxx_MO_START_COMMENT syntaxes to generate machining operation information in the APT source file. A sample PP Table (PPTableSampleMOComment.pptable) is delivered in the ..\startup\manufacturing\PPTables folder.

NC_AXIAL_MO_START_COMMENT

For axial machining operations:

	*START_NC_INSTRUCTION NC_AXIAL_MO_START_COMMENT 
	*START_SEQUENCE 
	PPRINT NC_AXIAL_MO_START_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
	PPRINT PATTERN NAME = %MFG_PATTERN_NAME 
	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID  
	PPRINT NC_AXIAL_MO_START_COMMENT END 
	*END 
	*END

The following example shows the type of APT source that can be generated:

	PPRINT NC_AXIAL_MO_START_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = Drilling 
	PPRINT OPERATION NAME = Drilling.1 
	PPRINT PATTERN NAME = Hole.1 
	PPRINT TOOL ASSEMBLY = Drill_Diam10 
	PPRINT NC_AXIAL_MO_START_COMMENT END 
	PPRINT OPERATION NAME : Drilling.1 
	$$ Start generation of : Drilling.1 
	LOADTL/2,1 
	SPINDL/ 204.0000,SFM,CLW 
	RAPID 
	GOTO / 130.00000, -55.00000, 2.50000 
	CYCLE/DRILL, 52.886751, 2.500000, 0.200000,MMPR 
	GOTO / 130.00000, -55.00000, 0.00000 
	CYCLE/OFF

NC_3X_MO_START_COMMENT

For 3-axis milling operations:

		*START_NC_INSTRUCTION NC_3X_MO_START_COMMENT 
 	*START_SEQUENCE 
 	PPRINT NC_3X_MO_START_COMMENT BEGIN 
 	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
 	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
 	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
 	PPRINT NC_3X_MO_START_COMMENT END 
 	*END 
 	*END

NC_5X_MO_START_COMMENT

For 5-axis milling operations:

		*START_NC_INSTRUCTION NC_5X_MO_START_COMMENT 
 	*START_SEQUENCE 
	 PPRINT NC_5X_MO_START_COMMENT BEGIN 
 	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
 	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
 	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
 	PPRINT NC_5X_MO_START_COMMENT END 
 	*END 
 	*END

NC_LATHE_MO_START_COMMENT

For turning operations:

		*START_NC_INSTRUCTION NC_LATHE_MO_START_COMMENT 
	 *START_SEQUENCE 
	 PPRINT NC_LATHE_MO_START_COMMENT BEGIN 
	 PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	 PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
 	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
	 PPRINT NC_LATHE_MO_START_COMMENT END 
	 *END 
	 *END

NC_MILL_MO_START_COMMENT

For 2.5-axis milling operations:

		*START_NC_INSTRUCTION NC_MILL_MO_START_COMMENT 
	 *START_SEQUENCE 
	 PPRINT NC_MILL_MO_START_COMMENT BEGIN 
 	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
 	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
 	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
 	PPRINT NC_MILL_MO_START_COMMENT END 
 	*END 
 	*END

End Comments

You can use NC_xxx_MO_END_COMMENT syntaxes to generate automatically instructions in the APT output at the end of Machining Operations (stop spindle rotation, stop coolant, axis locking / unlocking, deactivating a working mode, and so on) and to easily recognize the end of operations. This allows the PP to stop reading ahead of the APT if it is searching an instruction only inside the current operation, for example. This avoids the need to manually insert APT words, which is not always possible.

NC_AXIAL_MO_END_COMMENT

For axial machining operations:

		*START_NC_INSTRUCTION NC_AXIAL_MO_END_COMMENT 
 	*START_SEQUENCE 
 	PPRINT NC_AXIAL_MO_END_COMMENT BEGIN 
 	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
 	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
 	PPRINT PATTERN NAME = %MFG_PATTERN_NAME 
 	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID  
 	PPRINT NC_AXIAL_MO_END_COMMENT END 
 	*END 
 	*END

The following example shows the type of APT source that can be generated:

		$$ End generation of : Drilling.1 
 	PPRINT NC_AXIAL_MO_END_COMMENT BEGIN 
 	PPRINT MACHINE OPERATION = Drilling 
 	PPRINT OPERATION NAME = Drilling.1 
 	PPRINT PATTERN NAME = Hole.1 
 	PPRINT TOOL ASSEMBLY = Drill_Diam10 
 	PPRINT NC_AXIAL_MO_END_COMMENT END 
 	PPRINT OPERATION NAME : Drilling.1

NC_3X_MO_END_COMMENT

For 3-axis milling operations:

	*START_NC_INSTRUCTION NC_3X_MO_END_COMMENT 
	*START_SEQUENCE 
	PPRINT NC_3X_MO_END_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
	PPRINT NC_3X_MO_END_COMMENT END 
	*END 
	*END

NC_5X_MO_END_COMMENT

For 5-axis milling operations:

	*START_NC_INSTRUCTION NC_5X_MO_END_COMMENT 
	*START_SEQUENCE 
	PPRINT NC_5X_MO_END_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
	PPRINT NC_5X_MO_END_COMMENT END 
	*END 
	*END

NC_LATHE_MO_END_COMMENT

For turning operations:

	*START_NC_INSTRUCTION NC_LATHE_MO_END_COMMENT 
	*START_SEQUENCE 
	PPRINT NC_LATHE_MO_END_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
	PPRINT NC_LATHE_MO_END_COMMENT END 
	*END 
	*END

NC_MILL_MO_END_COMMENT

For 2.5-axis milling operations:

	*START_NC_INSTRUCTION NC_MILL_MO_END_COMMENT 
	*START_SEQUENCE 
	PPRINT NC_MILL_MO_END_COMMENT BEGIN 
	PPRINT MACHINE OPERATION = %MFG_MO_TYPE 
	PPRINT OPERATION NAME = %MFG_MO_IDENTIFIER 
	PPRINT TOOL ASSEMBLY = %MFG_TL_ASMBLY_ID 
	PPRINT NC_MILL_MO_END_COMMENT END 
	*END 
	*END

Other NC Commands

Note: Parameters listed under a context have to be used in the same context (where it makes sense) and should not be extended to other contexts.

NC Commands	Comments
`NC_AXIS_LOCK`	Allows blocking a linear or rotary axis. See Displacing and Locking Linear and Rotary Axes.
`MFG_AXIS_LOCK_STATUS`	Defines the lock status of the NC axis.
`MFG_NCAXIS_NAME`	Defines the name of NC axis.
`NC_AXIS_MOVE`	Allows linear displacement. See Displacing and Locking Linear and Rotary Axes.
`MFG_NCAXIS_NAME`	Defines the name of the NC axis.
`MFG_AXIS_POSITION`	Defines the position of the NC axis
`NC_CHANGE_REF_PT`	Defines the tool compensation corresponding to the desired tool output point.
`MFG_QUADRANT`	Defines the number of the compensation type (for example, 2 for compensation type P2).
`MFG_NOSE_RADIUS`	Defines the insert nose radius.
`MFG_TL_SET_X`	Defines the tool assembly set length in x direction.
`MFG_TL_SET_Y`	Defines the tool assembly set length in y direction.
`MFG_TL_SET_Z`	Defines the tool assembly set length in z direction.
`MFG_LGTH_COR_REG`, `MFG_TOOL_COMP` `MFG_TL_COMP`	Define the number of the correction register.

By default, the syntax is:

SWITCH/% MFG_QUADRANT

Syntax example for turning operations:

	SWITCH/%MFG_TL_COMP,%MFG_QUADRANT,INCR,%MFG_TL_SET_X, 
	%MFG_TL_SET_Z,%MFG_NOSE_RADIUS

NC Commands	Comments
`NC_COMMENT`
`MFG_MO_COMMENT`	Defines the comment on the Machining Operation.

By default, the syntax is

% MFG_MO_COMMENT

NC Commands	Comments
`NC_COMPENSATION`
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TL_COMP_RAD`	Defines the tool compensation radius.
`MFG_TL_NUMBER`	Defines the tool number associated to the compensation.
`MFG_TL_NAME`	Defines the name of tool associated to the compensation.

By default, the syntax is

LOADTL/% MFG_TL_NUMBER ,%MFG_TL_COMP

NC Commands	Comments
`NC_CUTCOM_ON`	The syntax of this NC command is `CUTCOM/ON` and cannot be parameterized.
`NC_CUTCOM_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_NORMDS_ON`	The syntax of this NC command is `CUTCOM/SAME, NORMDS` and cannot be parameterized.
`NC_CUTCOM_NORMDS_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_NORMPS_ON`	The syntax of this NC command is `CUTCOM/NORMPS` and cannot be parameterized.
`NC_CUTCOM_NORMPS_OFF`	The syntax of this NC command is `CUTCOM/OFF` and cannot be parameterized.
`NC_CUTCOM_LEFT`	The syntax of this NC command is `CUTCOM/LEFT` and cannot be parameterized.
`NC_CUTCOM_RIGHT`	The syntax of this NC command is `CUTCOM/RIGHT` and cannot be parameterized.

NC Commands

Comments

NC_DELAY

MFG_DELAY_UNIT

Defines the delay units from two values:

First value: delay expressed in number of revolutions.
By default, the value is REV.
Second value: delay expressed in seconds.
By default, the value is a blank string (represented by 8 underscore characters). When the statement is generated by the application this string is ignored.

MFG_DELAY_VALUE

Defines the numerical value of the delay.

By default, the syntax is

DELAY/%MFG_DELAY_VALUE,&MFG_DELAY_UNIT

NC Commands

Comments

NC_FEEDRATE

MFG_FEED_UNIT

Defines the feedrate unit.

This is done from a list with two values:

First value: feedrate expressed in model units per minute.
By default, the value is MMPM
Second value: feedrate expressed in model units per revolution.
By default, the value is MMPR

MFG_FEED_VALUE

Defines the numerical value of the feedrate.

By default, the syntax is

FEDRAT/% MFG_FEED_VALUE,&MFG_FEED_UNIT

NC Commands	Comments
`NC_MACHINING_AXIS`
`MFG_NCAXIS_IDENTIFIER`	See Displacing and Locking Linear and Rotary Axes Defines the NC-Axis identifiers, as the name of the Manufacturing Program for the first output, otherwise as the name of the machining axis change.
`MFG_SPINDLE_NAME`	Defines the name of the spindle that is linked to the origin.
`MFG_SPINDLE_NUMBER`	Defines the number of the spindle that is linked to the origin.
`MFG_NCAXIS_X_ORIG` `MFG_NCAXIS_Y_ORIG` `MFG_NCAXIS_Z_ORIG`	Defines the coordinates of the machining axis origin.
`MFG_NCAXIS_X_VECX` `MFG_NCAXIS_Y_VECX` `MFG_NCAXIS_Z_VECX`	Defines the components of the x-axis.
`MFG_NCAXIS_X_VECY` `MFG_NCAXIS_Y_VECY` `MFG_NCAXIS_Z_VECY`	Defines the components of the y-axis.
`MFG_NCAXIS_X_VECZ` `MFG_NCAXIS_Y_VECZ` `MFG_NCAXIS_Z_VECZ`	Defines the components of the z-axis.

By default, the syntax is

	$$*CATIA0 
	$$ %MFG_NCAXIS_IDENTIFIER 
	$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ 
    %MFG_NCAXIS_X_ORIG 
	$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY	
    %MFG_NCAXIS_Y_VECZ 
	   %MFG_NCAXIS_Y_ORIG 
	$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ 
    %MFG_NCAXIS_Z_ORIG

NC Commands	Comments
`NC_MULTAX_ON`	The syntax of this NC command is `MULTAX` and cannot be parameterized.
`NC_MULTAX_OFF`	The syntax of this NC command is `MULTAX/OFF` and cannot be parameterized.

NC Commands	Comments
`NC_PITCH`
`MFG_THREAD_PITCH`	Defines the thread pitch.
`MFG_NUM_THREADS`	Defines the number of threads.

Syntax examples:

PITCH/%MFG_THREAD_PITCH

	PITCH/(1/%MFG_THREAD_PITCH),MULTRD,%MFG_NUM_THREADS 
	FEDRAT/%MFG_THREAD_PITCH,MMPR

NC Commands	Comments
`NC_SPINDLE_ON`	The syntax of this NC command is `SPINDL/ON` and cannot be parameterized.
`NC_SPINDLE_START` `NC_SPINDLE`
`MFG_SPNDL_UNIT`	Defines the spindle speed unit. This is done from a list with two values: First value: spindle rotation expressed in revolutions per minute. By default, the value is `RPM.` Second value: spindle rotation expressed in surface meters per minute. By default, the value is `SMM.`
`MFG_SPNDL_WAY`	Defines the spindle direction. This is done from a list with two values: First value: spindle rotation processed clockwise. By default, the value is `CLW.` Second value: spindle rotation processed counter-clockwise. By default, the value is `CCLW.`
`MFG_SPNDL_SPEED`	Defines the numerical value of the spindle speed.
`MFG_SPNDL_DIAMTR`	Defines the diameter of the tool where the spindle speed is taken into account.
`NC_SPINDLE_LATHE`	Corresponds to the part spindle speed.
`NC_SPINDLE_STOP`	Note: this NC command is available to allow compatibility with previous versions. However, whenever possible, use `NC_SPINDLE_LOCK` or `NC_SPINDLE_OFF` instead of `MFG_SPNDL_STOP`.
`MFG_SPNDL_STOP`	List with two values defining the action applied to the spindle: First value: de-activation of the spindle. By default, the value is `OFF.` Second value: spindle locked in an indexed position. By default, the value is `LOCK.`
`NC_SPINDLE_LOCK`	The syntax of this NC command is `SPINDL/LOCK` and cannot be parameterized.
`NC_SPINDLE_OFF`	The syntax of this NC command is `SPINDL/OFF` and cannot be parameterized.

By default, the syntax is

SPINDL/%MFG_SPNDL_SPEED,&MFG_SPNDL_UNIT, 
		&MFG_SPNDL_WAY

NC Commands	Comments
`NC_THREAD_TURN`
`NC_THREAD_TURN_OFF`	Ends a `NC_THREAD_TURN` statement.

Syntax examples

THREAD/TURN

	 *START_NC_COMMAND         
	 NC_THREAD_TURN_OFF 
		THREAD/OFF 
	 *END

NC Instructions

For a given machine tool (i.e. post-processor), you can define sequences of PP word syntaxes associated to particular NC instructions.

General Information

NC instructions are either Auxiliary Command Type NC Instructions or PP Tables and PP Word Syntaxes

A syntax comprises a major word and one or more syntax elements such as minor words, numerical values and standard parameters. A set of standard parameters is associated to each NC instruction. Parameters may be combined in arithmetical expressions.

A syntax that includes parameters is a parameterized syntax (see examples below):

	*START_NC_INSTRUCTION   NC_TOOL_CHANGE 
	*START_SEQUENCE 
	TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM 
	TPRINT/%MFG_TOOL_NAME 
	LOADTL/%MFG_TOOL_NUMBER 
	*END 
	*END

	*START_NC_INSTRUCTION      NC_TAPPING 
	*START_SEQUENCE 
	CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP 
	*END 
	*END

Notes:

The % character indicates a parameter.
You can define one or more syntax sequences for each NC instruction.

For an example of how to define syntax sequences in NC Instructions, refer to the Define PP Word Syntax.

Auxiliary Command Type NC Instructions

NC Commands	Comments
`NC_ACTIVITY_HEADER`	Valuates parameters of an activity during the generation of APT.

By default, the syntax is (empty)

 
		*START_NC_INSTRUCTION      NC_ACTIVITY_HEADER		 
		*START_SEQUENCE  
		*END  
		*END

Syntax example

$$ OPERATION NAME = %MFG_MO_IDENTIFIER

NC Commands	Comments
`NC_END_MACRO`	Defines the Part Operation identifier.
`MFG_IDENTIFIER`	Defines the Part Operation identifier.
`MFG_MACHINE_NAME`	Defines the machine name.

By default, the syntax is

SPINDL/OFF

NC Commands	Comments
`NC_HEAD_ROTATION`	See Displacing and Locking Linear and Rotary Axes.
`MFG_TYPE_OF_ROT`	Defines the rotation type. (absolute angle in this version).
`MFG_DIR_OF_ROT`	Defines the rotation direction (clockwise or counterclockwise).
`MFG_AMOUNT_ROT`	Defines the angle of rotation around the axis of rotation.
`MFG_AXIS_OF_ROT`	Defines the axis of rotation on the machine head.
`MFG_ABC_AXIS`	Defines the axis of rotation on the machine head to get Minor word AAXIS, BAXIS, or CAXIS.

By default, the syntax is

ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT

NC Commands	Comments
`NC_ORIGIN`
`MFG_NCAXIS_X_ORIG`, `MFG_NCAXIS_Y_ORIG` `MFG_NCAXIS_Z_ORIG`	Defines the coordinates of the origin.
`MFG_ORIGIN_NUMBER`	Defines the origin number.
`MFG_ORIGIN_GROUP`	Defines the origin group.

NC Commands	Comments
`NC_PROGRAM_HEADER`
`MFG_PROGRAM_NAME`	Defines the name of the Manufacturing Program.
`MFG_CHANNEL_NUMBER`	Defines the channel number (Turret).

By default, the syntax is

 
	*START_NC_INSTRUCTION      NC_PROGRAM_HEADER
	*START_SEQUENCE  
	*END  
	*END

Syntax example

PROG_NAME,%MFG_PROGRAM_NAME

NC Commands	Comments
`NC_START_MACRO`
`MFG_IDENTIFIER`	Defines the Part Operation identifier.
`MFG_PROGRAM_NAME`	Defines the name of the Manufacturing Program.
`MFG_MACHINE_NAME`	Defines the machine name.
`MFG_MODEL_NAME`	Defines the name of the CATProcess (with document suffix).
`MFG_PRODUCT_NAME`	Defines the name of the CATProduct/CATPart (with no document suffix).

By default, the syntax is

PARTNO PART TO BE MACHINED

Note: When PARTNO is defined as a major word with text, if you want to use PARTNO with parameters for a CLFile output, the "/" character must be replaced by a space. You can use the "/" character for an APT output.

NC Commands	Comments
`NC_TABLE_ROTATION`	See Displacing and Locking Linear and Rotary Axes.
`MFG_TYPE_OF_ROT`	Defines the rotation type. (absolute angle in this version).
`MFG_DIR_OF_ROT`	Defines the rotation direction (clockwise or counterclockwise).
`MFG_AMOUNT_ROT`	Defines the angle of rotation around the axis of rotation.
`MFG_AXIS_OF_ROT`	Defines the axis of rotation on the machine head.
`MFG_ABC_AXIS`	Defines the axis of rotation on the machine head to get Minor word AAXIS, BAXIS, or CAXIS.

By default, the syntax is

ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT

NC Commands	Comments
`NC_TOOL_CHANGE`	If tool assembly resources are not used in your process, the term tool assembly means tool or cutter in the following description.
`MFG_TL_ASMBLY_ID`	Defines the tool assembly identifier.
`MFG_TL_SET_LGTH`	Defines the tool set length.
`MFG_NOMINAL_DIAM`	Defines the cutting diameter of the tool.
`MFG_TOOL_COMMENT`	Associates a comment to the resource.
`MFG_TOOL_NUMBER`	Defines the tool number.
`MFG_ASS_COMMENT`	Associates a comment to the resource.
`MFG_WEIGHT_SNTX`	Specifies the tool weight syntax.
`MFG_COOLNT_SNTX`	Specifies the coolant supply syntax.
`MFG_TOOTH_DES`	Allows to specify the tooth nature as a comment. For example, it could be the supplier reference of the insert.
`MFG_DIAMETER_2`	Defines the diameter 2 of the tool assembly.
`MFG_MAX_MIL_TIME`	Specifies the tool life in time units.
`MFG_MAX_MIL_LGTH`	Specifies the tool life in length units.
`MFG_CORNER_RAD`	Defines the radius of the cutting shape of the tool.
`MFG_CUT_ANGLE`	Defines the cutting angle of the tool.
`MFG_LENGTH`	Defines the length of the external envelope of the active part of the tool.
`MFG_TL_TIP_LGTH`	Defines the part of the tool that cannot be used for cutting material at the correct diameter (non-functional part of the tool).
`MFG_CUT_LENGTH`	Defines the effective cutting length available on the active part of the tool.
`MFG_NB_OF_FLUTES`	Defines the number of flutes on the tool. In case of tools with separate inserts, this is the number of inserts.
`MFG_TOOL_NAME`	Associates a name to the resource.
`MFG_TL_SET_X`	Defines the tool set length in x direction.
`MFG_TL_SET_Y`	Defines the tool set length in y direction.
`MFG_WAY_OF_ROT`	Defines the rotation orientation of the current element. It should be compatible with spindle rotation orientation. It can be RIGHTHAND or LEFTHAND.
`MFG_TOOL_ASS_POW`	Specifies the computed tool assembly power type If fixed, the value is TURN otherwise, the value is MIL
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_2`	Defines the value of the second tool compensation length
`MFG_FEED_MACH`(*)	Defines the machining feedrate.
`MFG_SPNDL_MACH` (*)	Defines the machining spindle speed.
`MFG_FEED_UNIT`(*)	Defines the feedrate unit.
`MFG_SPNDL_UNIT`(*)	Defines the spindle speed unit.

Note: (*) The values of these feed and speed attributes are taken from the first machining operation under the tool change.

By default, the syntax is

TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM

NC Commands	Comments
`NC_TOOL_CHANGE_LATHE`
`MFG_TL_ASMBLY_ID`	Defines the tool assembly identifier.
`MFG_ASS_COMMENT`	Associates a comment to the resource.
`MFG_TOOL_NAME`	Associates a name to the resource.
`MFG_TOOL_COMMENT`	Associates a comment to the resource.
`MFG_INSERT_COMMENT`	Associates a comment to the resource.
`MFG_QUADRANT`	Defines the number of the compensation type (for example, 2 for compensation type P2).
`MFG_SETUP_ANG`	Defines the tool assembly setup angle, in degrees.
`MFG_TL_SET_X`	Defines the tool set length in x direction.
`MFG_TL_SET_Y`	Defines the tool set length in y direction.
`MFG_TL_SET_Z`	Defines the tool set length in z direction.
`MFG_HAND_STYLE`	Defines the resource hand style. It can be LEFT_HAND, RIGHT_HAND or NEUTRAL.
`MFG_TOOL_INVERT`	Defines if the insert-holder has been inverted with respect to the original insert-holder style. Possible values are 0 (not inverted) or 1 (inverted).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Defines the value of the insert-holderl compensation length.
`MFG_LIFE_TIME`	Not available for groove inserts. Specifies the life time of the insert.
`MFG_NOSE_RADIUS`	Specifies the nose radius of the insert.
`MFG_CLEAR_ANGLE`	Defines the clearance angle.
`MFG_INSERT_LGTH`	Defines the cutting edge length of an insert.
`MFG_INSCRIB_DIAM`	Specifies the diameter of the inscribed circle of the insert.
`MFG_INSERT_ANGLE`	Defines the angle of the insert mounted on the tool.
`MFG_SPNDL_WAY`	Defines the spindle direction.
`MFG_FEED_MACH`(*)	Defines the machining feedrate.
`MFG_SPNDL_MACH`(*)	Defines the machining spindle speed.
`MFG_FEED_UNIT`(*)	Defines the feedrate unit.
`MFG_SPNDL_UNIT` (*)	Defines the spindle speed unit.

By default, the syntax is

TOOLNO/%MFG_TOOL_NUMBER,%MFG_NOMINAL_DIAM

Note: (*) The values of these feed and speed attributes are taken from the first machining operation under the tool change.

Displacing and Locking Linear and Rotary Axes

Default format for a linear displacement

	PPFUN/ <Letter of the axis>,<Letter of the axis>AXIS,value of the 
	displacement

Customized in the PP table

By means of NC_AXIS_MOVE

	/ 
	*START_NC_COMMAND NC_AXIS_MOVE 
	CLAMP/OFF,%MFG_NCAXIS_NAME,%MFG_AXIS_POSITION 
	*END 
	/

Format for a rotary displacement:

	ROTABL/value of the rotation,<rotary direction >,<rotation axis>

Customized in the PP table

By means of the NC instructions NC_TABLE_ROTATION, NC_MACHINING_AXIS and NC_HEAD_ROTATION.

		/ 
		*START_NC_INSTRUCTION NC_HEAD_ROTATION 
		*START_SEQUENCE 
		ROTHED/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT 
		*END 
		*END 
		/ 
		*START_NC_INSTRUCTION NC_TABLE_ROTATION 
		*START_SEQUENCE 
		ROTABL/%MFG_AMOUNT_ROT,%MFG_DIR_OF_ROT,%MFG_ABC_AXIS 
		*END 
		*END 
		/ 
		*START_NC_INSTRUCTION NC_MACHINING_AXIS 
		*START_SEQUENCE 
		$$ %MFG_NCAXIS_IDENTIFIER 
		$$ %MFG_NCAXIS_X_VECX %MFG_NCAXIS_X_VECY %MFG_NCAXIS_X_VECZ 
				 %MFG_NCAXIS_X_ORIG 
		$$ %MFG_NCAXIS_Y_VECX %MFG_NCAXIS_Y_VECY %MFG_NCAXIS_Y_VECZ 
	    %MFG_NCAXIS_Y_ORIG 
		$$ %MFG_NCAXIS_Z_VECX %MFG_NCAXIS_Z_VECY %MFG_NCAXIS_Z_VECZ 
	    %MFG_NCAXIS_Z_ORIG 
		CATMAT/%MFG_NCAXIS_X_ORIG,%MFG_NCAXIS_Y_ORIG,%MFG_NCAXIS_Z_ORIG,
	    %MFG_NCAXIS_X_VECX,%MFG_NCAXIS_X_VECY,%MFG_NCAXIS_X_VECZ,
     %MFG_NCAXIS_Y_VECX,%MFG_NCAXIS_Y_VECY,%MFG_NCAXIS_Y_VECZ,
	    %MFG_NCAXIS_Z_VECX,%	MFG_NCAXIS_Z_VECY,%MFG_NCAXIS_Z_VECZ,
	    %MFG_NCAXIS_IDENTIFIER 
		*END 
		*END

Blocked axix

LOCK/ <Letter of the axis>,<Letter of the axis>AXIS,ON

Customized in the PP table

By means of NC_AXIS_LOCK.

	 / 
		*START_NC_COMMAND NC_AXIS_LOCK 
		CLAMP/%MFG_AXIS_LOCK_STATUS,%MFG_NCAXIS_NAME 
		*END 
		/

Axial Machining Operation Type NC Instructions

For axial machining operations, the standard parameters are either:

parameters defined on the corresponding machining operation (geometrical data, machining strategy parameters, feeds and speeds, and so on)
parameters that are calculated according to an application method.

Examples

In the figures below:

the detail depth (MFG_DETAIL_DEPTH), total depth (MFG_TOTAL_DEPTH) and total depth up to the tool compensation point (MFG_TOTAL_DEPTH_COMP) are computed parameters.
the breakthrough distance (MFG_BREAKTHROUGH) is a machining strategy parameter
the tool tip length is a geometric attribute of the tool (MFG_TL_TIP_LGTH).

The overall breakthrough is the breakthrough distance plus the tool tip length.

Figure 1 showing Total depth without breakthrough
Figure 2 showingTotal depth with breakthrough (The figures below show Depth mode behavior on axial operations with chamfering machining):
Figure 3 showing Spot Drilling with Depth mode=By Tip
Figure 4 showing Countersinking with Depth mode=By Diameter

NC_BACK_BORING

General parameters are as follows.

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_CLEAR_TIP_2`	Defines the second approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_LIFT_MODE`	Defines the shift mode (0: None / 1: Linear coordinates / 2: Polar coordinates).
`MFG_XOFF`	Defines a shift along X.
`MFG_YOFF`	Defines a shift along Y.
`MFG_ZOFF`	Defines a shift along Z.
`MFG_LIFT_ANGLE`	Defines a shift angle.
`MFG_LIFT_DIST`	Defines a shift distance.
`MFG_RETRACT_CLEAR_TIP`	Defines a retract clearance.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_BCK_BORE_VAL`	Defines the back bore depth.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
`MFG_CMP_OFFSET`	Computes the offset.
`MFG_CMP_ANGLE`	Computes the shift angle. This parameter is computed if Shift mode is set to 'Linear coordinates'. Otherwise, the Shift angle is returned as is.

By default, the syntax is

CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_DIST`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING_SPINDLE_STOP

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_LIFT_MODE`	Defines the shift mode (0: None / 1: Linear coordinates / 2: Polar coordinates).
`MFG_XOFF`	Defines a shift along X.
`MFG_YOFF`	Defines a shift along Y.
`MFG_ZOFF`	Defines a shift along Z.
`MFG_LIFT_ANGLE`	Defines a shift angle.
`MFG_LIFT_DIST`	Defines a shift distance.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
`MFG_CMP_OFFSET`	Computes the offset.
`MFG_CMP_ANGLE`	Computes the shift angle. This parameter is computed if Shift mode is set to 'Linear coordinates'. Otherwise, the Shift angle is returned as is.

By default, the syntax is

CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BORING_AND_CHAMFERING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_CHAMFER_FEED_VALUE` `MFG_CHAMFER_FEED`	Defines the machining feedrate for chamfering phase.
`MFG_CHAMFER_SPINDLE_VALUE`	Defines the machining spindle speed for chamfering phase.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_CLEAR_TIP_2`	Defines the second approach clearance
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_2`	Specifies the length number of the second corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.
`MFG_TOOL_COMP_DIST_2`	Defines the distance between the position of the second corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER` `MFG_CHAMFER_VAL`	Defines the chamfer diameter.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_BREAK_CHIPS

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_AXIAL_DEPTH`	Defines the maximum depth of cut.
`MFG_OFFSET_RET`	Defines the retract offset.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
`MFG_EFFCT_DEPTH`	Defines the effective depth (= maximum depth of cut).

By default, the syntax is

CYCLE/BRKCHP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_CIRCULAR_MILLING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.
`MFG_RADIAL_STEP`	Defines the distance between paths.
`MFG_RADIAL_NB`	Defines the number of paths.
`MFG_AXIAL_STRAT`	Defines the axial strategy (1: Max depth of cut / 2: Number of levels / 3: Number of levels without top).
`MFG_AXIAL_DEPTH`	Defines the maximum depth of cut.
`MFG_AXIAL_NUMBER`	Defines the number of levels.
`MFG_SEQUENCING_STRAT`	Defines the sequencing mode (1: Radial first / 2: Axial first).
`MFG_TOLER_MACH`	Defines the machining tolerance.
`MFG_DIR_CUT`	Defines the direction of cut (1: Climb / 2: Conventional).
`MFG_OVERHANG`	Defines the percentage of overlap.
`MFG_DRAFT_ANGLE`	Defines the automatic draft angle.
`MFG_CIRCULAR_MODE`	Defines the machining mode (1: Standard / 2: Helical).
`MFG_HELIX_MODE`	Defines the helix mode (1: By pitch / 2: By angle).
`MFG_HELIX_ANGLE`	Defines the helix angle.
`MFG_PITCH`	Defines the pitch.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.

the syntax is

CYCLE/CIRCULARMILLING,%MFG_TOTAL_DEPTH, 
		%MFG_CLEAR_TIP

NC_COUNTERBORING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/BORE,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_COUNTERSINKING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 4 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

the syntax is

CYCLE/CSINK,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_DEEPHOLE

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_AXIAL_DEPTH`	Defines the maximum depth of cut.
`MFG_OFFSET_RET`	Defines the retract offset.
`MFG_DEPTH_DEC`	Defines the decrement rate.
`MFG_DEPTH_LIM`	Defines the decrement limit.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.
`MFG_EFFCT_DEPTH`	Defines the effective depth (= maximum depth of cut).

By default, the syntax is

CYCLE/DEEPHL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_DRILLING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.

By default, the syntax is

CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH, 
		&MFG_FEED_UNIT

NC_DRILLING_DWELL_DELAY

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_LATHE_THREADING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_THREAD_MACHINING`	Defines the machining type (1: Constant depth / 2: Section of cut).
`MFG_THREAD_PENETRATION`	Defines the penetration (1: Straight / 2: Flank / 3: Alternate).
`MFG_THREAD_UNIT`	Defines the unit (1: Pitch / 2: Thread per inch).
`MFG_THREAD_PROFILE`	Defines the profile (1: ISO / 2: Trapezoidal / 3: UNC / 4: Gaz).
`MFG_THREAD_ORIENTATION`	Defines the orientation (1: Internal / 2: External).
`MFG_THREAD_PITCH`	Defines the thread pitch.
`MFG_NUM_THREADS`	Defines the number of threads.
`MFG_THRD_PER_UNIT`	Specifies the threads per inch.
`MFG_FIR_PATH`	Defines the boolean for first passes (0: No / 1: Yes).
`MFG_LAS_PATH`	Defines the boolean for last passes (0: No / 1: Yes).
`MFG_SPR_PATH`	Defines the boolean for spring passes (0: No / 1: Yes).
`MFG_NUM_FIR_PATH`	Defines the number of first passes.
`MFG_NUM_LAS_PATH`	Defines the number of last passes.
`MFG_NUM_SPR_PATH`	Defines the number of spring passes.
`MFG_FIR_SECT_CUT`	Defines the section of cut for first passes.
`MFG_LAS_DEPT_CUT`	Defines the depth of cut for last passes.
`MFG_FIR_SECT_RAT`	Defines the section ratio between first passes and next passes.
`MFG_CRES_DIA_CLR`	Defines the clearance on the crest diameter.
`MFG_ENTER_ANG`	Defines the entry angle.
`MFG_LEAD_IN_DIST`	Defines the lead-in distance.
`MFG_LIFT_OFF_ANG`	Defines the lift-off angle.
`MFG_LIFT_OFF_DIS`	Defines the lift-off distance.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit. This is done from a list with two values: First value: spindle rotation expressed in revolutions per minute. By default, the value is RPM. Second value: spindle rotation expressed in surface meters per minute. By default, the value is SMM.
`MFG_SPNDL_WAY`	Defines the spindle direction. This is done from a list with two values: First value: spindle rotation processed clockwise. By default, the value is CLW. Second value: spindle rotation processed counter-clockwise. By default, the value is CCLW.
`MFG_SPNDL_SPEED`	Defines the numerical value of the spindle speed.

Computed parameters are as follows:

NC Commands	Comments
`MFG_ST_THRD_AX`	Defines the axial coordinate of the start thread on the crest.
`MFG_ST_THRD_RAD`	Defines the radial coordinate of the start thread on the crest.
`MFG_END_THRD_AX`	Defines the axial coordinate of the end thread on the crest.
`MFG_END_THRD_RAD`	Defines the radial coordinate of the end thread on the crest.
`MFG_END_THRD1_AX`	Defines the axial coordinate of the end thread on the root.
`MFG_END_THRD1_RAD`	Defines the radial coordinate of the end thread on the root.
`MFG_THRD_DEL_RAD`	Defines the depth of thread according to the radial axis.
`MFG_THRD_ANG`	Defines the angle of the thread. If different from zero, this angle indicates a conical thread.
`MFG_NOM_DIAM`	Defines the nominal diameter of the thread.
`MFG_THRD_LENGTH`	Defines the length of the thread.
`MFG_NB_PATH`	Defines the number of passes. First, last and spring passes are not included.
`MFG_DEPTH_CUT`	Defines the depth of cut.
`MFG_SECTION_CUT`	Defines the section of cut for passes that follow the first passes.
`MFG_THREAD_DEPTH`	Defines the depth of thread.

By default, the syntax is

CYCLE/THREAD,%MFG_THREAD_PITCH

NC_REAMING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/REAM,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_REVERSE_THREADING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_THREAD_DIAMETER`	Defines the thread diameter.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_TOOL_PITCH`	Defines the pitch value of the tool.

By default, the syntax is

CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_SPOT_DRILLING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 3 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_T_SLOTTING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_LENGTH`	Defines the slot height (= Tool length, which is read on tool).
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/TSLOT,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_TAPPING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_THREAD_DIAMETER`	Defines the thread diameter.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_TOOL_PITCH`	Defines the pitch value of the tool.

By default, the syntax is

CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_THREAD_WITHOUT_TAP_HEAD

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_THREAD_DIAMETER`	Defines the thread diameter.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.

By default, the syntax is

CYCLE/TAP,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP

NC_THREAD_MILLING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_THREAD_STRATEGY`	Defines the thread milling mode (1: Mono-pass / 2: Optimized passes).
`MFG_THREAD_DIRECTION`	Defines the thread milling direction (1: Top to bottom / 2: Bottom to top).
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_BREAKTHROUGH`	Defines the breakthrough distance.
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_JUMP_DIST`	Defines the jump distance.
`MFG_THREAD_DIAMETER`	Defines the thread diameter.
`MFG_PITCH`	Defines the pitch.
`MFG_PITCH_SENS` `MFG_PITCH_WAY_OF_ROT`	Defines the thread direction (1: Left-hand / 2: Right-hand).

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_TOOL_PITCH`	Defines the pitch value of the tool.

By default, the syntax is

CYCLE/THREADMILLING,%MFG_TOTAL_DEPTH, 
		%MFG_CLEAR_TIP

NC_TWO_SIDES_CHAMFERING

General parameters are as follows:

NC Commands	Comments
`MFG_MO_TYPE`	Defines the machining operation type.
`MFG_MO_IDENTIFIER`	Specifies the machining operation name or identifier.
`MFG_PATTERN_NAME`	Specifies the machining pattern name.

Feeds and Speeds parameters are as follows:

NC Commands	Comments
`MFG_FEED_APP_MODE`	Specifies the approach feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_APP_VALUE` `MFG_FEED_APPRCH`	Defines the approach feedrate.
`MFG_FEED_PLUNGE_MODE` `MFG_FEED_PL_TYPE`	Defines the plunge feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_PLUNGE_VALUE` `MFG_PLUNGE_FEED`	Defines the plunge feedrate.
`MFG_FEED_MACH_VALUE` `MFG_FEED_MACH`	Defines the machining feedrate.
`MFG_SPINDLE_MACH_VALUE` `MFG_SPNDL_MACH`	Defines the machining spindle speed.
`MFG_FEED_RETRACT_MODE` `MFG_FEED_RT_TYPE`	Defines the retract feedrate mode (0: Value / 1: Rapid).
`MFG_FEED_RETRACT_VALUE` `MFG_FEED_RETRACT`	Defines the retract feedrate.
`MFG_FEED_UNIT`	Defines the feedrate unit.
`MFG_SPNDL_UNIT`	Defines the spindle speed unit.

Machining Strategy parameters are as follows:

NC Commands	Comments
`MFG_CLEAR_TIP`	Defines the approach clearance.
`MFG_CLEAR_TIP_2`	Defines the second approach clearance.
`MFG_DEPTH_MODE`	Defines the depth mode (1: Tip / 2: Shoulder).
`MFG_PLUNGE_MODE`	Defines the plunge mode (0: None / 1: Tip / 3: Diameter).
`MFG_PLUNGE_TIP`	Defines the plunge tip distance.
`MFG_PLUNGE_OFFST`	Defines the plunge tip offset.
`MFG_PLUNGE_DIAMETER`	Defines the plunge diameter.
`MFG_DWELL_MODE`	Defines the dwell mode (0: None / 1: By revolutions / 2: By time).
`MFG_DWELL_REVOL`	Defines the dwell delay in revolutions.
`MFG_DWELL_TIME`	Defines the dwell delay in time units (seconds).
`MFG_TOOL_COMP` `MFG_TL_COMP`	Specifies the length number of current corrector.
`MFG_TOOL_COMP_1`	Specifies the length number of the first corrector.
`MFG_TOOL_COMP_DIST`	Defines the distance between the position of the current corrector and the tool tip.
`MFG_TOOL_COMP_DIST_1`	Defines the distance between the position of the first corrector and the tool tip.

Geometry parameters are as follows:

NC Commands	Comments
`MFG_DIAMETER`	Defines the nominal diameter of the tool.
`MFG_NOMINAL_DIAMETER`	Defines the nominal diameter of the machined feature.
`MFG_JUMP_DIST`	Defines the jump distance.

Computed parameters are as follows (see Figure 1 and Figure 2 above):

NC Commands	Comments
`MFG_DETAIL_DEPTH`	Computes the hole depth that is effectively machined.
`MFG_TOTAL_DEPTH`	Computes the total depth machined by the operation. This includes the hole depth, breakthrough, and tool tip length.
`MFG_TOTAL_DEPTH_COMP`	Computes the total depth machined by the operation up to the tool compensation point selected for the operation. This includes hole depth, breakthrough, and tool tip length up to the compensation point.
`MFG_PLUNGE_DIST`	Whatever the selected plunge mode (by Tip or by Diameter), this parameter returns the plunge distance. The plunge offset is taken into account in this value.
`MFG_CMP_DWL_TIME`	Computes the dwell delay (in time units of seconds): this parameter is computed if dwell mode is set to 'revolutions'. Otherwise, the dwell time is returned as is.

By default, the syntax is

CYCLE/DRILL,%MFG_TOTAL_DEPTH,%MFG_CLEAR_TIP,%MFG_FEED_MACH, 
		&MFG_FEED_UNIT

Probing Operations

You can insert PP Words for Probing operations.

Parameters for Probing Operations

See Probing Operations and Parameters > Probing Operations in Prismatic Machining User's Guide for more information.

NC Commands	Comments
`MFG_PROBING_CONTACT_DEPTH`	Defines the depth of penetration of the stylus into the material.
`MFG_PROBING_DEPTH_DST`	Defines the depth Distance. By default, the value is 0mm.
`MFG_PROBING_DIRECTION_X` `MFG_PROBING_DIRECTION_Y` `MFG_PROBING_DIRECTION_Z`	Defines the probing direction, i.e. direction of the first probing. By default, the value is 1., 0., 0.
`MFG_PROBING_DIST_PROBE`	Defines the distance between the first and the second probing points.
`MFG_PROBING_FIRST_PROBE`	Defines the distance between the corner and the first probing point.
`MFG_PROBING_HOLE_DIAMETER`	Defines the theoretical diameter. By default, the value is 0.mm.
`MFG_PROBING_NB_PROB`	Defines the number of probing points. By default, the value is 4. It must be greater than 0.
`MFG_OFFSET_ON_TOP_PLANE`	Defines the offset on the top plane. By default, the value is 0.mm.
`MFG_PROBING_RETURN_BY_MIDLE`	After each probe, the retract goes through the middle of the hole (or the pin).
`MFG_PROBING_RETURN_BY_TOP_PLANE`	After each probe, the retract goes through the top plane.
`MFG_PROBING_SAFETY_DST`	Defines the safety distance. By default, the value is 10.mm.
`MFG_PROBING_SECURITY_DST`	Defines the distance before contact with part that requires to change the feedrate in probing feedrate. By default, the value is 5mm.
`MFG_PROBING_SIDE`	Defines the probing side.
`MFG_PROBING_SLOT_WIDTH`	Defines the theoretical width.
`MFG_PROBING_TOLERANCE`	Defines the probing tolerance used in the computation of the tool path.

Examples:

Hole Probing operation: PPTable:

*START_NC_INSTRUCTION NC_PROBING_HOLE 
*START_SEQUENCE 
CYCLE/HOLE_PROBING, 
%MFG_PROBING_NB_PROB, %MFG_PROBING_HOLE_DIAMETER, %MFG_PROBING_SAFETY_DST, %MFG_PROBING_DEPTH_DST, %MFG_OFFSET_ON_TOP_PLANE, 
%MFG_PROBING_DIRECTION_X, %MFG_PROBING_DIRECTION_Y, %MFG_PROBING_DIRECTION_Z 
*END 
*END

Generated APT File: The selected point coordinates are (0.0, 10.0, 0.0).

$$ OPERATION NAME: Hole Probing.1 
$$ Start generation of: Hole Probing.1 
LOADTL/1,1 
TLAXIS/ 0.00, 0.00, 1.00 
SPINDL/ 0.00,RPM,CLW 
RAPID 
GOTO / 0.00, 10.00, 10.00 
CYCLE/HOLE_PROBING, 4, 10.00, 10.00, 5.00, 0.00, 1.00, 0.00, 0.00 
GOTO / 0.00, 10.00, 20.00 
CYCLE/OFF 
$$ End of generation of: Hole Probing.1

Slot Probing operation: PPTable:

*START_NC_INSTRUCTION NC_PROBING_SLOT
*START_SEQUENCE
CYCLE/SLOT_PROBING, %MFG_PROBING_SLOT_WIDTH,
%MFG_PROBING_SAFETY_DST,
%MFG_PROBING_DEPTH_DST, %MFG_OFFSET_ON_TOP_PLANE,
%MFG_PROBING_DIRECTION_X, %MFG_PROBING_DIRECTION_Y,
%MFG_PROBING_DIRECTION_Z
*END
*END

Generated APT File:

$$ OPERATION NAME: Slot Probing.1
$$ Start generation of: Slot Probing.1
LOADTL/1,1
TLAXIS/ 0.00, 0.00, 1.00
SPINDL/ 0.00,RPM,CLW
RAPID
GOTO / 0.00, 10.00, 10.00
CYCLE/SLOT_PROBING, 10.00, 10.00, 5.00, 0.00, 1.00, 0.00,
0.00
GOTO / 0.00, 10.00, 20.00
CYCLE/OFF
$$ End of generation of: Slot Probing.1

Corner Probing operation: PPTable:

*START_NC_INSTRUCTION NC_PROBING_CORNER 
*START_SEQUENCE 
CYCLE/INT_CORNER_PROBING, %MFG_PROBING_SAFETY_DST, %MFG_PROBING_DEPTH_DST, 
%MFG_OFFSET_ON_TOP_PLANE 
*END 
*END

Generated APT File: All macro motions are deactivated.

$$ OPERATION NAME: Int. Corner Probing.1 
$$ Start generation of: Int. Corner Probing.1 
LOADTL/1,1 
TLAXIS/ 0.000000, 0.000000, 1.000000 
SPINDL/ 0.0000,RPM,CLW 
RAPID 
GOTO / 0.00000, 10.00000, 10.00000 
CYCLE/INT_CORNER_PROBING, 10.00000, 5.00000, 0.00000 
GOTO / 0.00000, 10.00000, 20.00000 
CYCLE/OFF 
$$ End of generation of: Int. Corner Probing.1

Multi-Points Probing operation: PPTable:

*START_NC_INSTRUCTION NC_PROBING_MULTIPOINTS 
*START_SEQUENCE 
VERIFY/ MULTI_PROBING, %MFG_PROBING_SAFETY_DST 
*END 
*END

Generated APT File: All macro motions are deactivated.

$$ OPERATION NAME: Multi Probing.1 
$$ Start generation of: Multi Probing.1 
LOADTL/1,1 
TLAXIS/ 0.000000, 0.000000, 1.000000 
SPINDL/ 0.0000,RPM,CLW 
RAPID 
GOTO / 0.00000, 10.00000, 10.00000 
CYCLE/MULTI_PROBING, 10.00000, 5.00000, 0.00000 
GOTO / 17.64900, 70.69300, 30.58600, -0.40615, 0.26639, 0.87411 
GOTO / 59.80300, 68.11100, 39.42300, 0.07485, 0.26853, 0.96035 
GOTO / 20.88300, 27.77500, 31.39400, -0.31938, -0.28117, 0.90496 
CYCLE/OFF 
$$ End of generation of: Multi Probing.1