Creating a Sequential Turning Operation

You can create a Sequential Turning operation in the Manufacturing Program.

Related Topics
Sequential Turning

  1. Activate the Manufacturing Program and click Sequential Turning in the Lathe Machining Operations toolbar.

    A Sequential Turning entity is added to the Manufacturing Program. The Sequential Turning operation dialog box appears with the Geometry tab .

  2. Select the Strategy tab .



  3. Still in the Strategy tab .

    1. Select Go and define the first motion parameters.



      Note: The first motion must be a Go motion to a point.

    2. Click check representation (Red lines) in the Geometry tab to select desired check element in the 3D view.
    3. Click OK to define the motion.
    4. Select Go again to define the second motion parameters.
    5. Successively select the check representation in the Geometry tab and select the desired check elements in the 3D view.
    6. Set the first and second Check Modes to To.



    7. Set a Offset on Check to 2mm for first check element.
    8. Click OK to define the motion.

    9. Select Go again to define the next motion.
    10. Click check representation in the Geometry tab and then select the desired check element in the 3D view.
    11. Set the Check Mode to Past.
    12. Set a Offset on Check element to 5mm.
    13. Click OK to define the motion.
    14. Select Go InDirv .
    15. Select the drive direction in the Geometry tab then the desired linear element in the 3D view.
    16. Select a check representation in the Geometry tab then select the desired check element in the 3D view.
    17. Set the Check Mode to To.
    18. Click OK to define the motion.

    19. Select Follow .

      The check curve of the previous motion is used as drive curve. This drive element is highlighted in the 3D view

    20. Select a check representation in the Geometry tab and then select the desired check element in the 3D view.
    21. Set the Check Mode to To.
    22. Click OK to define the motion.

    23. Select PP Word , then specify a PP word (DELAY/5, for example) in the dialog box that appears.
    24. Select Go Delta
    25. Set the check mode to Line and distance in Geometry tab.
    26. Select the line representation in the dialog box then the desired linear element in the 3D view.
    27. Enter a distance.
    28. Click OK to define the motion.

      The defined motions are shown below.

  4. Right-click any motion to access the contextual menu.


    • Column Order: Allows to change the header column order with Up and Down buttons.

    • Column Filter: Allows to filter the header columns.
    • Properties: Allows to modify the selected motion.
    • Delete: Removes the selected motion.
    • Cut: Cut the selected motion.
    • Copy: Copy the selected motion.

  5. Go to the Tool tab to select a tool.

    See Specifying a Tool Element in a Machining Operation

  6. Select the Feeds and Speeds tab to specify the feedrates and spindle speeds for the Machining Operation.

  7. Select the Macros tab to specify the operation's transition paths.

    See Define Macros on a Lathe Operation for more information.

  8. Click Tool Path Replay to check the validity of the Machining Operation.

    See Replaying the Tool Path


    • The tool path is computed.
    • A progress indicator is displayed.
    • You can cancel the tool path computation at any moment before 100% completion.


  9. Click OK to create the Machining Operation.