Creating Swept Volumes

You can create a swept volume by sweeping out a closed profile in planes normal to a spine curve while taking other user-defined parameters (such as guide curves and reference elements) into account.

This task also deals with:

This task shows you how to:

Before you begin: Create a 3D shape containing sketches and curves.
Related Topics
Creating Swept Surfaces Using an Explicit Profile
Creating Swept Surfaces Using a Linear Profile
Creating Swept Surfaces Using a Circular Profile

Create a Swept Volume with an Explicit Profile

You can create a swept volume by sweeping out an explicit profile taking other user-defined parameters (such as guide curves and reference elements) into account.

With reference surface

You can create a swept volume with explicit profile by defining reference surface and guide curve.

  1. Click Volume Sweep in the Volumes toolbar.

    The Swept Volume Definition dialog box appears.

  2. Click the Explicit profile type icon.

  3. In the Subtype list, select With reference surface.



  4. In the Profile box, select a profile to be swept out.

  5. In the Guide curve box, select a curve.

  6. Select a surface (by default, the reference surface is the mean plane of the spine) in order to control the position of the profile during the sweep. Note that in this case, the guiding curve must lie completely on this reference surface, except if it is a plane. You can impose an angle on this surface.



  7. Click OK to create the swept volume.

With two guide curves

You can create a swept volume with an explicit profile by defining two guide curves.

  1. Click Volume Sweep .

    The Swept Volume Definition dialog box appears.

  2. Click the Explicit Profile type icon.

  3. In the Subtype list, select With reference surface.



  4. In the Profile box, select the profile to be swept out.

  5. In the Guide curve 1 box, select a guide curve.

  6. In the Guide curve 2 box, select a second guide curve.



    You can also specify anchor points for each guide. These anchor points are intersection points between the guides and the profile's plane or the profile itself, through which the guiding curves will pass.

    There are two anchoring types:


    • Two points: select anchor points on the profile that will be matched respectively to guide curve 1 and 2. These points must belong to the sweeping plane of the profile. If the profile is open, these points are optional and the extremities of the profile are used.
    • Point and direction: select an anchor point on the profile which will be matched onto guide curve 1 and an anchor direction.
    Sweep without positioning Two points anchoring type

    Sweep without positioning Point and direction anchoring type

    If you do not explicitly select anchor points or anchor direction, they are automatically computed if the profile is planar. Note that the selection is still available. The anchor points are computed as follows:


    • For Anchor point 1: intersection between the profile plane and Guide curve 1 (I1).
    • For Anchor point 2: intersection between the plane, passing through Anchor point 1 and normal to the spine, with Guide curve 2 (I2).
    • For Anchor direction: line between I1 and I2.


    Automatic computation for Two points anchoring type

    Automatic computation for Point and direction anchoring type

  7. Click OK to create the swept volume.

With pulling direction

You can create a swept volume with explicit profile by defining pulling direction and guide curve.

The With pulling Direction subtype is equivalent to the With reference surface subtype with a reference plane normal to the pulling direction.

  1. Click Volume Sweep .

    The Swept Volume Definition dialog box appears.

  2. Click the Explicit Profile type icon.

  3. In the Subtype list, select With pulling direction.



  4. In the Profile box, select the profile to be swept out.

  5. In the Guide curve box, select the curve.

  6. In theDirection box, select a direction.



  7. Click OK to create the swept volume.

Create a Swept Volume with a Linear Profile

You can create swept volume with a linear profile by defining guide curve and draft direction.

  1. Click Volume Sweep .

    The Swept Volume Definition dialog box appears.

  2. Click the Line Profile type icon.

    The With draft direction sub-type is automatically selected and grayed out.

  3. Select a guide curve (closed planar curve or any surface (planar or non-planar)) and a draft direction (a line, a plane or components).

  4. Select the draft computation mode:


    • Square: a plane normal to the draft direction is used as the reference surface and the projection of the guide curve onto this plane is used as the spine.
    • Cone: envelop of cones defined along a given curve. In order to have swept start and end planes similar as the square mode, the guide curve needs to be extrapolated and the resulting volume split.

  5. Choose the angular definition:


    • Wholly defined: the angular value varies during the whole sweeping operation.
    Important: In this tab, you can click Law... to display the Law Definition dialog box. For further information, refer to Creating Swept Surfaces Using a Linear Profile.

    • G1-Constant: a different draft value for every G1 section can be set; in this case, a relimiting plane is requested when defining lengths
    • Location values: on given points on the curve, angular values can be defined.
    Warning: This tab is only available for a square computation mode and will work only on G1 curves.

  6. Choose the length types:


    • From curve: the swept volume starts from the curve
    • From/Up to: the length is computed by intersecting a plane or a surface; a point can be selected: a plane parallel to the draft plane would be computed
    • From extremum: the lengths are defined along the draft direction from an extremum plane; L1 corresponds to the "maximum plane" in the draft direction, L2 corresponds to the "minimum plane" in the draft direction.




  7. Click OK to create the swept volume.

Create a Swept Volume with a Circular Profile

You can create a swept volume with a circular profile by defining the center curves and other parameters.

The following subtypes are available:


Center and reference curve

You can create a swept volume with circular profile by defining center and reference curves.

  1. Click Volume Sweep .

    The Swept Volume Definition dialog box appears.

  2. Click the Circle profile icon.

  3. Select Center and reference curve from the Subtype list.



  4. Select a Center curve and a Reference curve.

  5. Define a fixed radius if needed.

    No fixed radius defined

    Fixed radius = 40mm

  6. Click OK to create the swept volume.

Center and radius

You can create a swept volume with circular profile by defining center curve and radius.

  1. Click Volume Sweep .

    The Swept Volume Definition dialog box appears.

  2. Click the Circle profile icon.

  3. Select Center and radius from the Subtype list.



  4. Select a Center curve (DemoCurve2) and enter a Radius value (10mm).



  5. Click OK to create the swept volume.

Preview the Angular Value

You can preview the various solutions you can get after completion of operation.

Important: This option is available with:
  • Explicit profile: With reference surface and With pulling direction sub-types.
  • Linear profile: With draft direction sub-type.

When creating a swept volume, you are now able to preview the four solutions based on the values given for the Angle and Lengths. The first solution corresponds to Angle, Length1 and Length2 values, the second solution to -Angle, Length1 and Length2 values, the third solution to Angle, Length2 and Length1 values, and the fourth solution to -Angle, Length2 and Length1 values.



The orange arrow corresponds to the current solution.

  • Click on any arrow then on Preview or OK to recompute the swept volume. You can also use the Previous or Next buttons or enter a solution number in the Angular sector box:



Define Relimiters

You can define relimiters to get expected swept volume.

  • Relimiters can be selected on a closed curve (curve, spine, or default spine). In that case, you are advised to define points as relimiters, as plane selection may lead to unexpected results due to multi-intersection.
  • You can relimit the default spine, thus avoiding to split it to create the swept volume.

  • Select a relimiter in the Relimiter 1 and/or the Relimiter 2 boxes.

    Below is an example with a plane as Relimiter 1:

Smooth

You can define the smoothing parameters on the swept volumes.

  1. Check Angular correction to smooth the sweeping motion along the reference surface. This may be necessary when small discontinuities are detected with regards to the spine tangency or the reference surface's normal. The smoothing is done for any discontinuity which angular deviation is smaller than 0.5 degree, and therefore helps generating better quality for the resulting swept volume. By default, the angular correction is set to 0.5 degree.

  2. Check Deviation from guide(s) to smooth the sweeping motion by deviating from the guide curve(s). A Smoothing Curves is performed using correction default parameters in tangency and curvature. This option is not available for with tangency surface subtype.

Remove Twisted Areas

During creation or edition, you can generate swept surfaces that have a twisted area by delimiting the portions of the swept surface to be kept.

The generated surface is therefore composed of several unconnected portions.



  1. Select the Remove cutters on Preview check box to remove the twisted areas management each time you click on Preview. This option is selected by default.

  2. Use the Setback slider to define a distance to move all the cutters from the twisted areas. It is defined as a percentage of the guide length from 0 to 20%. Its default value is 2%.

  3. Select the Fill twisted areas check box to fill the twisted zones. It is activated by default.

    Warning:
    • When you select this check box, the Setback slider affects only the cutters that have not been previously moved.
    • If you have not manually moved any cutter, and if you replace the main guide of the sweep, the twisted areas are filled with the defined setback.

  4. Select the Compute C0 vertices as twisted areas check box to fill the C0 vertices areas taking into account the setback value.

    It is activated by default.

    Note: This option is unavailable with the With tangency surface and With two tangency surfaces subtypes of the linear profile, and One guide and tangency surface subtype of the circular profile.

  5. Use the Connection strategy drop-down list to choose the connection mode for the filled areas. The three options are:


    • Automatic: this mode chooses the best connection strategy depending on the geometry.
    • Standard: this mode maintains the sweep profile.
    • Similar to guide: this mode maintains the point continuity.
      Important:
      • These modes force the chosen connection.
      • If Similar to guide fails, then the Standard connection strategy is applied. If this mode also fails, no connection strategy is applied.

  6. Click the Add cutter button allows you to create cutters on the main guide of the sweep.

    Warning: If Fill twisted areas is selected, while the Add cutter button is clicked, the created cutters define a filled area. Otherwise, the cutters define a cutting zone.

Detect Canonical Shapes

You can detect the canonical shapes if they exist in the swept surface.

  • Select the Canonical Shape Detection check box to automatically compute regular shapes such as cylinders, cones and spheres. Moreover, it can automatically detect planar surfaces if they exist in the swept surface.

    By default, this option is not selected.

    Warning: This capability is not available with explicit profile.