Creating Swept Surfaces Using a Circular Profile

You can create a swept surface that uses a circular profile by defining three guide curves.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Three Guides from the Subtype drop-down list.

   
   
   

3. Select three guide curves.

4. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

5. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.
   
   

You can create a swept surface that uses a circular profile by defining two guide curves and radius of the circular profile.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Two guides and radius from the Subtype drop-down list.

   
   
   

3. Select two guide curves and enter a Radius value.

   You can then choose between six possible solutions (among them, two new complete circular solutions) by clicking the Previous or Next button or entering a solution number in the Solution(s) field.
   
   Choosing a circular solution (radius=45)

4. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

5. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.
   
   

You can create a swept surface that uses a circular profile by specifying a center and two angles.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Center and two angles from the Subtype drop-down list.

   
   
   

3. Select a Center Curve and a Reference angle curve.

   You can relimit the swept surface by entering two angle values.
   
   

4. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

5. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.

You can create a swept surface that uses a circular profile by defining a center and radius of the circular profile.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Center and radius from the Subtype drop-down list.

   
   
   

3. Select a Center Curve and enter a Radius value.

   
   
   

4. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

5. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.

You can create a swept surface that uses a circular profile by defining two guide curves and tangency surface. The tangency surface will be tangent to the swept surface.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Two guides and tangency surface from the Subtype drop-down list.

   
   
   

3. Select two guide curves, and a reference surface to which the sweep is to be tangent.

4. Depending on the geometry, there may be one or two solutions from which to choose. The solution displayed in red shows the active sweep.

   
   
   

5. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

6. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.
   
   

You can create a swept surface that uses a circular profile by defining a guide curve and tangency surface.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select One guide and tangency surface from the Subtype drop-down list.

   
   
   

3. Select a guide curve, a reference surface to which the sweep is to be tangent, and enter a radius value.

   
   
   

4. Select theTrim with tangency surface option to perform a trim between the swept surface and the tangency surface. The portion of the tangency surface that is kept is chosen so that the final result is tangent.

   With Trim option selected
   
   
   With Trim option cleared
   
   

5. If needed, select a Spine to specify a spine different from the first guide curve or center curve. If the plane normal to the spine intersects one of the guiding curves at different points, it is advised to use the closest point to the spine point for coupling.

6. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.

You can create a swept surface that uses a circular profile by defining limit curve and tangency surface.

1. Click Sweep .

   The Swept Surface Definition dialog box appears.

2. Click the Circle icon and select Limit curve and tangency surface from the Subtype drop-down list.

   
   
   

3. Select a limit curve and a reference surface to which the sweep is to be tangent, and enter a radius value.

   You can relimit the swept surface by entering two angle values.
   
   

   Important: The limit curve should lie on the input surface. Angles are measured from the tangent plane.

4. If needed, select a Spine to specify a spine different from the limit curve.

5. Click OK to create the swept surface.

   The surface (identified as Sweep.xxx) is added to the specification tree.