Creating a Cutout

You can remove the material from the active body, based on a selected profile using the Cutout command.

Related Topics
More about Cutout Features
Creating Functional Features
Using the Display Only Parents Option to Retrieve a Creation Context

  1. Click Cutout in the Basic Features toolbar.

    The Cutout dialog box appears.



  2. Select the closed profile on which you are going to base the cutout.

    Tip: If no profile is defined, clicking Sketcher enables you to sketch the profile you need.



  3. The prism is the default shape. Just click Sweep if you want to change. For the purposes of our scenario, keep the default option. Set the parameters and options as follows to define the shape you want.


    • In the Distance tab, enter 17mm to define Floor: Length.
      Important: Instead of using the Length option, you can set the Through All option, which sets the value of the cutout length as zero. This extends the cutout infinitely from the profile plane in the specified direction. Because the cutout is a protected volume, the infinite volume is also protected.



      Preview of the Through All option defined for the Floor

      Opening: Length=0mm

      Here again, instead of using the Length option, you can set the Through All option, which sets the value of the cutout depth as zero.

    • In the Direction tab:

      Select the Normal to profile check box.

    • In the Draft tab:

      Angle=1deg

    • In the Fillet tab:

      Clear all fillet options.

  4. Click Preview to get an idea of what the cutout looks like. As a protected area, it is displayed in red:



  5. Clear the With floor check box to see the difference. As indicated by the cursor, the cutout has no floor.



  6. Select the With floor check box to create a floor.

  7. Define the wall direction to control whether the wall is constructed inside or outside of the selected profile. The default is an outside wall thickness.

  8. Define the wall by setting one of the two options available in the Wall area:


    • Use body thickness: the cutout wall thickness is that of the active shelled body thickness.

    • Enter thickness: simply enter the value you want. After this option is selected, the value box becomes available. Wall thickness values can only by positive values.

  9. For the purposes of our scenario, set the Enter thickness option and enter 2 mm in the value box.

  10. Click OK to confirm and create the cutout. Cutout.X is added to the specification tree in the Solid Functional Set.x node.