Creating a Quick Clipping View/Quick Clipping View Profile

You can create a quick clipping view using a circle as callout. You can also use a roughly sketched profile.

Before you begin: Open a generative drawing representation. To specify that the dimensions which are attached to non-visible geometry in clipping views should be put in no show mode automatically, make sure that Put in no show dimension on non-visible geometry is selected in Tools > Options > Mechanical > Drafting > View.
Related Topics
About Clippings
Modifying a Clipping

  1. Perform either of the following operations in the Views toolbar (Clippings sub-toolbar):

    • To create a quick clipping view, click Quick Clipping View .
    • To create a quick clipping view using a sketched profile, click Quick Clipping View Profile .

    Note: In this scenario, you will create a quick clipping view.

  2. Perform either of the following operations:

    • If you are creating a quick clipping view, select the center of the circle.
    • If you are creating a quick clipping view using a sketched profile, select the required points for sketching a polygon.



  3. Perform either of the following operations:

    • If you are creating a quick clipping view, drag the mouse to define the clipping profile and click to end its creation.
    • If you are creating a quick clipping view using a sketched profile, drag the mouse to define the clipping profile and double-click to end its creation.

    The quick clipping view and the associated profile result as shown here:



    Note: Note the existence of dimensions that are associated to a geometrical element which is not visible in the clipping view: these dimensions are placed in the no-show space. (When applicable, this is also the case of annotations that are associated to such a dimension, and of annotations that are no longer linked to the clipping view.) For more information, refer to View in the Customizing chapter.

  4. Click Swap visible space in the View toolbar.

    You can now visualize the dimensions (and annotations, when applicable) that no longer appear on the clipping view.

    Important: Dimensions are displayed in clipping views using the colors defined in Tools > Options > Mechanical > Drafting > Display tab, Activate element's analysis area. For more information, refer to Display.

  5. You can show these dimensions again on the clipping view. To do so, click Hide/Show in the View toolbar.

    Important: You can also select View Definition > Unclip from the contextual menu. However, selecting this option will not show the dimensions on the unclipped view.

  6. Select the dimension you want to show on the clipping view.

  7. Click Swap visible space again.

    The selected dimension now appears on the quick clipping view again.