Creating a Detail View/Detail View Profile

You can create a detail view from the 3D using either a circle or a sketched profile as callout.

Before you begin: Open a 3D part representation, then create a new drawing.
Related Topics
About Detail Views
Creating a Quick Detail View/Quick Detail View Profile

  1. Perform either of the following operations in the Views toolbar (Details sub-toolbar):

    • To create a circular detail view, click Detail View .
    • To create a detail view using a sketched profile, click Detail View Profile .

    In this scenario, you will create a circular detail view.

  2. Click the callout center.

    If you are creating a detail view using a sketched profile, create the required points for sketching a polygon.

  3. Drag to select the callout radius and click a point to end the selection.

    If you are creating a detail view using a sketched profile, double click to end the cutting profile creation. Note that if you do not close the profile, it will be closed automatically.



  4. Click to generate the detail view.

    The default scale is 2 (twice the scale of the active view). You will now modify this scale in the Properties dialog box.

  5. Right-click the detail view, select Properties and then the View tab.

  6. Enter the desired Parameters Scale, for example 3.

  7. Click OK to validate and exit the Properties dialog box.



    Important:
    • You can also modify the detail view profile through the Properties dialog box.
    • In the isometric view, you can move the detail text ("A" in this example) after detail view creation.