Creating 'Up to Surface' Pads

You can create pads using the Up to surface option.

Before you begin:

To perform this task, create a simple closed profile and a pad.

Related Topics
About Pads
Creating Pads

  1. Select the profile to be extruded.



  2. Click Pad in the Sketch-Based Features toolbar (Pads sub-toolbar).

    The Pad Definition dialog box appears and the application previews a pad with a default dimension value.

  3. In the Type box, set the Type option to Up to surface.

  4. Select the vertical circular face. This face belongs to the same body as the existing pad.

    Using the Up to surface option, you can select a face belonging to the same body as the sketch or a face belonging to Part Body. The face trims the extrusion.

    Tip: When choosing a surface, keep in mind that:
    • Contextual commands creating the surfaces you need are available from the Limit box:
    • Insert Operations > Create Join : joins surfaces or curves. See Generative Shape Design User's Guide: Performing Operations on Shape Geometry: Joining Surfaces or Curves.
    • Insert Operations > Create Extrapol : extrapolates surface boundaries or curves. See Generative Shape Design User's Guide: Performing Operations on Shape Geometry: Extrapolating Surfaces and Extrapolating Curves. If you create any of these elements, the application then displays the join or the extrapol icon in front of the Limit box. Clicking this icon enables you to edit the element.
    • You cannot use the same surface to trim both limits of a pad, even if you define an offset value for one of the limits.

  5. An Offset option is available in the dialog box. Enter -30 as the offset value. This offset is the distance between the surface and the top face of the pad to be created.

  6. Optional: Click Preview to see the result.

  7. Click OK.

    The pad is created. The specification tree indicates this creation.