Using the Clipping View

You can clip the 2D and 3D backgrounds of layout views using a circular or polygonal profile.

Note: In the case of an assembly layout, the clipping view is centered on the assembly.

Before you begin: Open a 3D shape representation containing a layout. Double-click a sheet in the specification tree to open the layout in the 2D window.
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More About Clipping Views

  1. Right-click the front view in the specification tree or in the sheet and select Clipping > Clip View.

    The Tools Palette is displayed with the Circular profile or Polygonal profile options for you to chose from (you can also select these options from the contextual menu).

  2. You can either:

    • Select Circular profile. The radius definition (R:) field appears in the Tools Palette.



      Click in the geometry to select the circle center. Then, enter the radius in the radius definition (R:) field, or drag the radius on the sheet.

    • Select Polygonal profile. The length (L:) and angle (A:) fields appear in the Tools Palette.



      Click in the geometry to select the first point and draw the profile as needed. Double-click or select the first point to end the profile creation.

    For the purpose of this scenario, we will pretend you created a circular profile. The manipulators are activated so that you can make modifications to the clipping profile if needed. You will not use the manipulators at this point, but later on in this scenario.

  3. Click to validate the profile.

    You can see that the view has been clipped.

  4. Right-click the clipped view in the specification tree or geometry and select Clipping > Modify Clipping.

    The manipulators of the clipped profile are activated.

  5. You can now reframe, resize and/or move the clipping frame according to your design needs:

    • To manipulate the control points: drag the yellow manipulators.
    • To resize the profile: drag the white manipulators.
    • To move the entire profile: drag the frame itself using one of its green dotted lines.

    For example, drag the white manipulators to resize the profile. The green dotted circular profile shows the clipping that will be obtained after the manipulation.

  6. Additionally, to change the color and linetype of the clipping outline, right-click the view and select Properties > Visualization tab, Clipping Outline area.



  7. Right-click the clipped view in the specification tree or geometry, and select Clipping > Unclip View to unclip the existing profile.

  8. Select Clipping > Replace Clipping from the contextual menu to replace the existing clipping view.

    The previous clipping is removed and a new clipping can be defined in the same way as when using the Clip View command. The graphic properties of the replaced profile are applied to the newly defined clipping profile.

You have learned how to use the clipping view.