Creating a Geometrical Tolerance

You can create a geometrical tolerance.

You can also copy an existing geometrical tolerance. You can set text properties either before or after you create the text.

Before you begin: Open a drawing representation.
Related Topics
More About Creating a Geometrical Tolerance
Copying Geometrical Tolerances

  1. Click Geometric Tolerance in the Annotations toolbar (Tolerancing sub-toolbar).

  2. Select an element (geometry, dimension, dimension value, text or point) or click in the free space to position the anchor point of the geometrical tolerance.


    • If you select an element, the anchor point will be an arrow. Note that you can modify this symbol by Handling Annotation Leaders.



    • If you select a point in the free space, the anchor point will be a small balloon.



    • If you select a dimension, the anchor point will be at the intersection of the dimension line and the extension line.



    • If you press the Shift key and select the extension line, the leader is perpendicular to the extension line and the anchor point corresponds to the position of the cursor when you click to create the geometrical tolerance.



    • If you select a dimension value or a text, no leader will be created. The geometric tolerance will be displayed just below and parallel to the element you selected.



  3. Move the cursor to position the geometrical tolerance and then click at the chosen location.

    The Geometrical Tolerance dialog box appears.

    Important:
    • At this step, you can apply the parameter values of an existing geometric tolerance to the tolerance you are creating: to do this, simply select the existing geometric tolerance.
    • If you have selected the Use style values to create new objects check box in Tools > Options > Mechanical > Drafting > Administration tab, the Geometrical Tolerance dialog box is pre-filled with custom style values (as defined in the Standards Editor). In this case, Properties toolbars and the Tools Palette are disabled during the creation of the geometrical tolerance.

      On the other hand, if you have not selected this option, the Geometrical Tolerance dialog box is pre-filled with the last entered values (if any). In this case, Properties toolbars and the Tools Palette are active during the creation of the geometrical tolerance.

    • You can reset the current style values in the Geometrical Tolerance dialog box at any time using the Reset button.

  4. Select the Filter Tolerance check box to filter the available tolerance symbols according to the type of geometrical element you selected, if any.

    Important: If you do not select any geometrical element, the tolerance symbols will not be filtered.

  5. Specify the tolerance type by clicking the Tolerance Symbol button and selecting the appropriate symbol.

  6. Type the tolerance value in the Tolerance value field, adding symbols as needed. To do this, position the cursor at the proper location in the field, and click the Insert Symbol button to choose the appropriate symbol.

    Important: You can add symbols to the tolerance and reference value as well as to the upper and lower text.

  7. Type the reference values in the Reference value fields, adding symbols as needed.

  8. To add a new geometrical tolerance, click the Next line arrow button and repeat steps 4 to 5.

  9. Type the upper and lower texts in the appropriate fields. You may also add symbols if you want to.



    The geometric tolerance is updated as you define values for each field.

  10. Click OK when you are done. The geometrical tolerance is created.



  11. You can add an all-around symbol to the leader. To do this, select the geometrical tolerance, right-click the yellow manipulator on the arrow and select Application Zone > All Around.