More About Welding Symbols

This sub-topic provides more information about how to define primary welding symbol, complementary symbol and finish symbol to create the welding symbol.

You can add the following welding symbols according to the dedicated standard.

This sub-topic provides miscellaneous information about welding symbols.

• If you have selected the Use style values to create new objects option in Tools > Options > Mechanical > Drafting > Administration tab, the Welding creation dialog box is pre-filled with custom style values (as defined in the Standards Editor). In this case, Properties toolbars and the Tools Palette are disabled during the creation of the welding symbol. On the other hand, if you have not selected this option, the Welding creation dialog box is pre-filled with the last entered values (if any). In this case, Properties toolbars and the Tools Palette are active during the creation of the welding symbol.
• You can reset the current style values in the Welding creation dialog box at any time using the Reset button.
• You can close the tail (reference) using a rectangle variable-size frame . For more information about adding frames, refer to Adding Frames or Sub-Frames.
• At any time, you can modify the welding symbol. To do this, double-click the welding symbol to be modified and enter the modifications in the displayed dialog box.

In a Generative Drafting context, Generative View Styles (GVS) enable you to specify whether weld features defined in 3D (in the Weld Design workbench) are to be represented symbolically in views.

For more information, refer to Generative Drafting User's Guide: Administration: Setting General Generative View Style Parameters: Generate Parameters.

If you create a view containing a weld symbolic representation using GVS, you can then create a welding symbol that will be associative to the 3D weld specification, by selecting either the side or the top representation of weld seams (even if they are hidden by other geometry). In this case, the Welding Creation dialog box will be pre-filled with the following information:

• Weld type (simple or double information)
• Weld length
• Weld thickness
• "Weld-all-around" symbol

The image below shows a welding symbol created on the top representation of a weld seam hidden by other geometry:

The image below shows a welding symbol created on the side representation of the weld seam:

Notes:

• When updating the drawing, if the 3D weld specification cannot be found (if it has been deleted for example), the welding symbol update fails. In this case, the welding symbol content is not modified, and it is displayed using the color specified by the Dimensions for which last update failed option in Tools > Options > Mechanical > Drafting > Display tab, in Elements Analysis area, selecting Activate elements' analysis check box, and clicking Configure . Refer to Settings Customization User's Guide: Mechanical Design Settings: Customizing Settings: Annotation and Dress-Up for more information.
• If you right-click an associative welding symbol, the Isolate and Query Object Links contextual commands are available from the contextual menu.
• You can also create dimensions on weld representations by selecting their profile. However, such dimensions are not associative and cannot drive the 3D. The image below shows a dimension created on the side representation of the weld seam.