Creating a Lip

You can create a lip using the Simple method.

1. Click Lip .

   The Lip dialog box appears.

   
   
   

2. Set Height to define the height of the upper lip. The value must be greater than zero.

3. Set Thickness to define the thickness of the lip. The value must be greater than zero.

4. Set Mating angle which defines the vertical edge (defined by the height) of the outside of the lip. A negative value implies a snap fit.

5. Set the Inside angle option: it defines the vertical edge (defined by the height) of the inside of the lip. A negative value implies a snap fit.

6. Select an edge or a curve to define the path.

7. Click OK.

You can create a lip using the Upper/Lower profile method.

1. Click Lip .

   The Lip dialog box appears.

2. Set the Upper/Lower profile method.

   You are going to define one lip for Divide.1 and another lip for Divide.2 (highlighted feature).

   
   
   

   Look more closely at the profiles already sketched:

   
   
   

   Note that profiles cannot be self-intersecting.

3. Select Sketch.3 as the upper profile.

4. Select Sketch.4 as the lower profile.

   
   
   

5. Selecting Protected volume protects the volume of the lip area by preventing any additional material created by other features to be added to the lip. For the purpose of our scenario, select the option.

6. The lip path consists of edges or curve, planar or non-planar. All edges must be connected, and the profile plane must intersect a portion of the path. By default, all split edges constitute the path. For the purpose of our scenario, deselect the option and select the edge as shown to restrict the creation of the lips.

   
   
   

7. Click OK to confirm the operation.

   Both lip features Upper Lip.1 and Lower Lip.2 are added to the specification tree. Each of them is located in a distinct Divide body.

   
   
   
   
   

8. Hide Divide Body.2 to make visualization easier. Lower Lip is created only on the selected edge and the protected area appears in red:

   
   
   

   Looking more closely, the shape looks like this:

   
   
   

9. Show Divide Body .2 and hide Divide Body.3 to see the second lip.

   
   
   

You can create a lip using the Center profile method.

1. To perform this scenario, delete Divide Body.3 so as to obtain only one divide feature.

2. Select Divide Body.2 in the specification tree and set it to Define In Work Object.

3. Click Lip .

4. Select the Center profile method.

   
   
   

5. Select Sketch.4 as the center profile.

   
   
   

   By default, the Protected volume option is not active. This protects the volume of the lip area by preventing any additional material created by other features to be added to the lip.

6. The lip path consists of edges or curve, planar or non-planar. By default, all split edges constitute the path.

7. Click OK to confirm the operation.

   
   
   

   Looking more closely, the shape looks like this: