From the Tools > Options... > Parameters and Measure
command, access the Knowledge tab and make sure
Interactive Synchronization at Load
is checked.
In Excel or in your text editor, create a table containing the following
columns:
'PartBody\Point.2\Z'(mm)
Part Number
30
25
75
-15
32
In CATIA, click Design Table
in the Knowledge toolbar.
The Creation of a Design Table dialog box is displayed. Enter
a name (DesignTable1 for example) and a comment.
Check Create a design table from a pre-existing file.
Click OK
The Design table source representation creation
or selection is displayed.
Click the From File tab and click Import.
Select the .xls or .txt file you have just created and
click Open. The New - Step 1 dialog box opens. Enter the name of
the Representation. Click Finish, and OK.
A dialog box asks you whether you want to perform automatic
associations between the design table columns and the document parameters
which have the same name.
In the DesignTable.1 window, Check Duplicate
data in CATIA model. Note that if this option is not
checked, you will not be able to generate a new file.
Click OK to apply the default configuration.
DesignTable.1 is displayed below the Relations node.
Save your file and close it.
Right-click DesignTable.1 in the specification tree and
select DesignTable.1 object>Export content to file.... The
New - Step 1 dialog box is displayed.
Enter the name of the representation and click Finish.
The following message displays:
Click Yes when asked if you want this file to
become the new design table source file. The representation containing the
design table data is created.
The representation containing the
design table data is created.