Sample 3

You can create here the sample that is used in all topics of the Parameters section and in some of the topics of the Formulas section.

Before you begin: Make sure Relations is active in the Tools > Options... > Infrastructure > 3D Shape Infrastructure >Display tab and select Parameters and Relations in the Tools > Options... > General > Display tab.
Related Topics
About Parameters
Creating a Parameter

  1. Select PLM Access > New.

  2. In the PLM Type dialog box, click Representation, 3D Shape and click Next.

  3. In the Name field, enter the name of your representation and click Finish.

  4. Click and select Mechanical Design > Part Design.

  5. Click Sketch in the Sketcher toolbar. The Sketcher workbench appears. Select the reference plane (xy plane) in the geometry area.

  6. Select Circle in the Wireframe toolbar. Click in the geometry area and drag the cursor to define the circle dimensions.

  7. Click Exit workbench in the Sketcher toolbar to exit the Sketcher.

  8. Extrude the circle to create a pad. To do so, click Pad .

    The Pad Definition dialog box appears and the application previews the pad to be created.

  9. Enter 40 in the Length field to increase the length value. Click OK. The pad is created.

    The specification tree indicates that it has been created.

  10. Click Hole to create a hole in the Pad.

  11. Select a Pad face. The Hole Definition dialog box appears and the application previews the hole to be created.

  12. Select Up to Next in the scrolling list and enter 65 in the Diameter field. Click OK when done.

  13. Click and select Shape > Generative Shape Design.

  14. Click Point in the Wireframe toolbar. The Point Definition dialog box appears. Select Circle / Sphere center in the Point type scrolling list and select Hole.1 in the geometry. Hole.1\Edge appears in the Circle / Sphere field. Click OK. .

    The point is created.

  15. Click Point in the Wireframe toolbar. The Point Definition dialog box appears. Enter the following values in the coordinates fields and click OK:


    • X = 15

    • Y = 30

    • Z = 45

  16. Create a line between these 2 points. Click Line in the Wireframe toolbar. The Line Definition dialog box appears. Click the 2 points and click OK.

    The line is created.

  17. Click Formula in the Knowledge toolbar. The Formulas dialog box appears. Select Length in the scrolling list and click New Parameter of type. Click OK.