Overloading Element Properties

You can overload the properties of 3D components in a view generated from a 3D product.

Before you begin: Open a drawing representation generated from a product.
Related Topics
About View Content Customization

  1. Right-click a section view, for example.

  2. Select Section view object > Overload properties.

    The Characteristics dialog box is displayed.



  3. In the view, select the element that you want to edit.

    This element is highlighted in the drawing and listed in the dialog box.



    Important: You can also select several elements, if you want to overload their properties in the same way. In the case of several elements generated from a single part instance, all these elements are highlighted when you select one. You can select the elements in the 3D document, either by selecting a node in the specification tree or by multi-selecting the elements in the specification tree.

  4. Select the element you want to edit in the dialog box and click Edit.

    The Editor dialog box is displayed.



    You can modify the following parameters:


    • Cut in section views: specifies that the 3D element will be cut in the section view, section cut or breakout view. Uncheck this option if you do not want an element to be cut in the view.

    • Use when projecting: specifies that the 3D element will be projected in the view. Uncheck this option if you do not want an element to be represented in the view (other 3D elements possibly hidden by this element in the view will then be visible in the view).

    • Represented with hidden lines: specifies that 3D hidden lines will be represented.

    • Shown: specifies that the dress-up (color, line type, etc.) associated to the 2D generated element will be shown. The view is not re-computed.

    • Graphic Properties area: lets you modify graphic properties such as element color, line type and line thickness.

  5. Clear the Shown check-box and click OK.

    The dress-up associated to the 2D generated element is no longer shown in the view.

  6. In the product's specification tree, select a PartBody.

    Back to the drawing, the elements of the PartBody have been added to the Characteristics dialog box.

  7. Select the elements in the list and click Edit.

  8. In the Editor dialog box, select the red color in the Graphic properties drop-down list and click OK.

  9. Back in the Characteristics dialog box, click Apply.

    A dialog box is displayed while the view is being re-computed.



  10. In the product's specification tree, press Ctrl and multi-select 3D elements.

    Back to the drawing, the elements have been added to the Characteristics dialog box.

  11. Select elements in the list and click Edit.

  12. In the Editor dialog box, clear the Shown check-box and click OK.

  13. Back in the Characteristics dialog box, click OK again.

    A dialog box is displayed while the view is being re-computed.